PEEK Machining Guide — Tips and Best Practices

PEEK (polyether ether ketone) is one of the most demanding engineering plastics to machine, but with the right tooling, parameters, and post-processing, the results are excellent. This guide covers the essentials of CNC machining PEEK — tool selection, cutting speeds, coolant strategy, stress relief, and common pitfalls to avoid.

Why PEEK Is Challenging to Machine

PEEK has a melting point of 343°C — far higher than most engineering thermoplastics. It is mechanically strong (tensile strength ~100 MPa), tough, and highly wear-resistant. These same properties that make PEEK exceptional in demanding applications create specific challenges during machining:

Heat buildup: PEEK has low thermal conductivity, so heat concentrates at the cutting zone rapidly. Excessive heat softens the material locally and degrades surface finish.
Residual stress: Semi-finished PEEK stock often contains internal stresses from the extrusion or compression molding process. Asymmetric material removal releases these stresses unevenly, causing warpage.
Tool wear: PEEK’s high strength and especially filled grades (glass fiber, carbon fiber) are highly abrasive to cutting tools.

Cutting Tool Selection

Tool choice is critical when machining PEEK:

Carbide tools: The minimum requirement for PEEK machining. Use uncoated or TiN-coated carbide inserts ground to sharp edges. Sharp cutting edges reduce heat generation and improve surface finish.
PCD tools (polycrystalline diamond): The best choice for filled PEEK grades (GF30, CF30). PCD edges resist abrasive wear many times longer than carbide and produce superior surface finishes.
HSS tools: Not suitable for PEEK. They dull quickly and generate excessive heat from friction rather than cutting.

Always use positive rake geometry (rake angle 0–15°) and ensure tools are sharp. A dull edge generates friction heat instead of cleanly shearing material.

Cutting Speeds and Feed Rates

The table below shows general recommendations for unfilled PEEK. For filled grades, reduce speeds by 20–30%.

Operation	Cutting Speed	Feed Rate	Depth of Cut
Turning (roughing)	150–300 m/min	0.10–0.25 mm/rev	1.0–3.0 mm
Turning (finishing)	200–400 m/min	0.05–0.10 mm/rev	0.2–0.5 mm
Milling	150–300 m/min	0.05–0.15 mm/tooth	1.0–3.0 mm
Drilling	60–150 m/min	0.05–0.15 mm/rev	—

Important: maintain adequate feed rates. Too low a feed causes the tool to rub rather than cut, generating heat without efficient chip removal.

Coolant and Chip Management

Three cooling strategies work well for PEEK machining:

Compressed air blast (recommended): The best general-purpose approach. It removes chips effectively and cools the cutting zone without introducing moisture. PEEK does not absorb significant moisture, but dry cooling simplifies the process and avoids contamination.
Flood coolant: Appropriate when heat generation is particularly high, such as deep-hole drilling or long-duration operations. Use water-soluble coolant. Avoid oil-based fluids that can leave residues on the surface.
Minimum quantity lubrication (MQL): A good compromise between air blast and flood coolant. Works well for turning and milling operations.

Tips for Turning, Milling, and Drilling

Turning

PEEK turns well with carbide inserts using positive rake geometry. Use a small nose radius (0.4–0.8 mm) for finishing to improve surface quality. Maintain at least 6° clearance angle to prevent the tool flank from rubbing the workpiece. When turning thin-walled PEEK parts, use soft jaws or internal support to prevent distortion from clamping forces.

Milling

Use 2–3 flute carbide end mills to ensure adequate chip clearance. Climb milling produces better surface finish than conventional milling. Symmetric material removal reduces stress release — machine both sides whenever possible. For pocketing, use helical entry or ramping rather than plunging to reduce heat concentration.

Drilling

Use carbide drills with a 118–130° point angle. Peck drilling is essential for deep holes to clear chips and manage heat buildup. Start with a pilot hole for precise positioning. Avoid excessive thrust force, which can cause cracking or delamination at the hole exit, especially in filled grades.

Stress Relief Annealing

Annealing is one of the most important steps in PEEK machining, especially for precision components. Machining releases internal stresses unevenly, which can cause dimensional changes over hours or days after the part leaves the machine.

Temperature: 150°C for unfilled PEEK. Glass- and carbon-filled grades can be annealed at up to 200°C.
Hold time: 2–4 hours depending on wall thickness. For sections thicker than 10 mm, allow 4 hours or more.
Heating and cooling: Ramp temperature slowly (max 20°C/hour) and allow the part to cool in the oven under controlled conditions. Rapid cooling can introduce new stresses.
Timing: Perform an intermediate anneal after roughing and a final anneal after finishing, particularly when tolerance requirements are tight.

Achievable Tolerances

With proper parameters and stress relief, PEEK parts can be machined to very tight dimensions:

General tolerances: ±0.05 mm is routinely achievable
Tight tolerances: ±0.02 mm is possible with intermediate annealing and finish machining
Surface finish: Ra 0.4–1.6 μm is achievable with finishing operations

Note that PEEK’s coefficient of thermal expansion is approximately 50 × 10⁻&sup6; /K, meaning a 10°C temperature change causes a 0.5 μm/mm dimensional shift. Always measure parts at a controlled temperature (20°C).

PEEK Grades for Machining

Selecting the right PEEK grade affects both machinability and end-use performance:

Unfilled PEEK (natural): Easiest to machine. Best surface finish and chemical resistance. Suitable for food-contact and medical applications. Tensile strength ~100 MPa.
PEEK GF30 (30% glass fiber): Higher stiffness and improved dimensional stability. Wears tools faster — PCD tooling recommended. Suitable for structural components.
PEEK CF30 (30% carbon fiber): Best strength-to-weight ratio and lowest thermal expansion. Highly abrasive to tools — use PCD or diamond-coated tooling. Aerospace and semiconductor applications.
PEEK + PTFE/graphite: Reduced coefficient of friction. Ideal for bearing and seal applications. Machines well with standard carbide tooling.

Common Problems and Solutions

Problem	Cause	Solution
Poor surface finish	Dull tool, feed rate too low, or excessive heat	Replace with sharp tool, increase feed, add air blast cooling
Warping after machining	Uneven release of residual stress	Machine symmetrically, add intermediate anneal, reduce material removal per pass
Dimensional drift	Residual stress and thermal expansion	Stress relief anneal, measure at controlled temperature, allow part to stabilize
Chips sticking to tool	Excessive heat at cutting zone	Reduce cutting speed, increase cooling, check tool sharpness
Cracking during drilling	Excessive thrust force, poor chip evacuation	Use peck drilling, reduce feed rate, use pilot hole

Summary

Machining PEEK requires care and attention, but it is not inherently difficult for an experienced machinist. The keys are sharp carbide or PCD tools, adequate feed rates, controlled heat generation, and stress relief annealing for precision parts. Following these fundamentals will consistently achieve ±0.05 mm tolerances and excellent surface quality.

Explore our PEEK material range and machined parts service — we supply both PEEK stock shapes and finished precision components to your drawings.

Need PEEK machining or stock material?

We supply PEEK rods, sheets, and tubes, and manufacture precision-machined PEEK components to your specifications. Tell us about your requirements and we’ll take it from there.